NX Open C++ Reference Guide
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Represents a Features::ThroughCurveMesh builder. More...
Represents a Features::ThroughCurveMesh builder.
Let you create a body from a collection of existing curve outlines (known as strings) running in two different directions.
To create a new instance of this class, use Features::FeatureCollection::CreateThroughCurveMeshBuilder
Default values.
Property | Value |
---|---|
Construction |
Normal |
CrossSurfaceRebuildData.RebuildType |
None |
CurvatureTolerance |
0.5 |
Emphasis |
Both |
FirstCrossContinuity.ContinuityType |
G0 |
FirstPrimaryContinuity.ContinuityType |
G0 |
IntersectionTolerance |
0.02 |
LastCrossContinuity.ContinuityType |
G0 |
LastPrimaryContinuity.ContinuityType |
G0 |
PositionTolerance |
0.0254 (millimeters part), 0.001 (inches part) |
PrimarySurfaceRebuildData.RebuildType |
None |
TangentTolerance |
0.5 |
Created in NX5.0.0.
NXOpen::Features::ThroughCurveMeshBuilder::BodyPreferenceTypes NXOpen::Features::ThroughCurveMeshBuilder::BodyPreference | ( | ) |
Returns the body type options
Created in NX7.5.0.
License requirements : None
Returns the cross curves list which is required.
They should all be roughly parallel and run in approximately one direction. A point could be selected as the first and/or last primary string.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
NXOpen::GeometricUtilities::Rebuild* NXOpen::Features::ThroughCurveMeshBuilder::CrossSurfaceRebuildData | ( | ) |
Returns the cross surface rebuild data, GeometricUtilities::Rebuild .
Redefine the degree and knot points of the cross strings to build a surface that joins smoothly with surrounding surfaces. It is only available for the Normal Construction option.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
Returns the cross template curve.
Control the building of the simple surface in cross curve direction. It is only available when the construction method is simple. If you leave it empty, the system will automatically choose the most complicated one for fitting.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
Returns the curvature tolerance.
Control the curvature tolerance of the rebuild surface in relation to the input curves.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
NXOpen::Features::ThroughCurveMeshBuilder::EmphasisType NXOpen::Features::ThroughCurveMeshBuilder::Emphasis | ( | ) |
Returns the emphasis options.
Allow you to tell the system which set of strings will have the most effect on the created surface in both location and shape.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
NXOpen::GeometricUtilities::Continuity* NXOpen::Features::ThroughCurveMeshBuilder::FirstCrossContinuity | ( | ) |
Returns the first cross continuity, GeometricUtilities::Continuity .
Define continuity constraint at the first cross sections side. It contains the continuity type and the constraint face.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
NXOpen::GeometricUtilities::Continuity* NXOpen::Features::ThroughCurveMeshBuilder::FirstPrimaryContinuity | ( | ) |
Returns the first primary continuity, GeometricUtilities::Continuity .
Define continuity constraint at the first primary sections side. It contains the continuity type and the constraint face.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
Returns the intersection tolerance.
Define how far the primary strings and cross strings can deviate from each other.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
NXOpen::GeometricUtilities::Continuity* NXOpen::Features::ThroughCurveMeshBuilder::LastCrossContinuity | ( | ) |
Returns the last cross continuity, GeometricUtilities::Continuity .
Define continuity constraint at the first cross sections side. It contains the continuity type and the constraint face.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
NXOpen::GeometricUtilities::Continuity* NXOpen::Features::ThroughCurveMeshBuilder::LastPrimaryContinuity | ( | ) |
Returns the last primary continuity, GeometricUtilities::Continuity .
Define continuity constraint at the last primary sections side. It contains the continuity type and the constraint face.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
Returns the position tolerance.
Control the distance accuracy of the rebuild surface in relation to the input curves.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
Returns the primary curves list which is required.
They should all be roughly parallel and run in approximately one direction. A point could be selected as the first and/or last primary string.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
NXOpen::GeometricUtilities::Rebuild* NXOpen::Features::ThroughCurveMeshBuilder::PrimarySurfaceRebuildData | ( | ) |
Returns the primary surface rebuild data, GeometricUtilities::Rebuild .
Redefine the degree and knot points of the primary strings to build a surface that joins smoothly with surrounding surfaces. It is only available for the Normal Construction option.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
Returns the primary template curve.
Control the building of the simple surface in primary curve direction. It is only available when the construction method is simple. If you leave it empty, the system will automatically choose the most complicated one for fitting.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
void NXOpen::Features::ThroughCurveMeshBuilder::SetBodyPreference | ( | NXOpen::Features::ThroughCurveMeshBuilder::BodyPreferenceTypes | bodyPreference | ) |
Sets the body type options
Created in NX7.5.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
bodyPreference | bodypreference |
void NXOpen::Features::ThroughCurveMeshBuilder::SetConstruction | ( | NXOpen::Features::ThroughCurveMeshBuilder::ConstructionMethod | construction | ) |
Sets the construction options.
Use one of three construction options when you create a Through Curve Mesh feature: Normal, Use Spline Points, and Simple.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
construction | construction |
void NXOpen::Features::ThroughCurveMeshBuilder::SetCurvatureTolerance | ( | double | tolerance | ) |
Sets the curvature tolerance.
Control the curvature tolerance of the rebuild surface in relation to the input curves.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
tolerance | tolerance |
void NXOpen::Features::ThroughCurveMeshBuilder::SetEmphasis | ( | NXOpen::Features::ThroughCurveMeshBuilder::EmphasisType | emphasis | ) |
Sets the emphasis options.
Allow you to tell the system which set of strings will have the most effect on the created surface in both location and shape.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
emphasis | emphasis |
void NXOpen::Features::ThroughCurveMeshBuilder::SetIntersectionTolerance | ( | double | tolerance | ) |
Sets the intersection tolerance.
Define how far the primary strings and cross strings can deviate from each other.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
tolerance | tolerance |
void NXOpen::Features::ThroughCurveMeshBuilder::SetPositionTolerance | ( | double | tolerance | ) |
Sets the position tolerance.
Control the distance accuracy of the rebuild surface in relation to the input curves.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
tolerance | tolerance |
void NXOpen::Features::ThroughCurveMeshBuilder::SetTangentTolerance | ( | double | tolerance | ) |
Sets the tangent tolerance.
Control the angle accuracy of the rebuild surface in relation to the input curves.It is expressed in degree.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
tolerance | tolerance |
Returns the spine.
Control the parameterization of the cross strings. It is valid only if both the first and last primary strings are planar and this spine string is perpendicular to the first and last primary strings
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")
Returns the tangent tolerance.
Control the angle accuracy of the rebuild surface in relation to the input curves.It is expressed in degree.
Created in NX5.0.0.
License requirements : features_modeling ("FEATURES MODELING"), nx_freeform_1 ("basic freeform modeling")